eagle board submission checklist

schematic check
    erc
    look for cross-sheet references that aren't connected
    add 2 fudicials, sparkfun lib-FIDUCIAL-1X2
    4 mounting holes
    add ground test points with holes for probe gnd
    check notes.txt file for todos
    create readme.txt with board name, zip content desc and fudicial placement, example below
    check that all operational output lines have pull up/down during reset
    make sure I2C SDA/SCL have pull-up resistors and solderable test points

board check
    put a silk square down for sharpie id marking
    add dimensions to tDocu
    load dru file, this sets spacing for pours, etc
    ratsnest
    run zoom-unrouted
	drc
    add company name to tNames
    add board name and version to tNames
    run normalize-text:
        set to 40 & 8 mils
        smashes all components
    place names with top, bottom off, tcream on
    place logo with import-bitmap, or use lib part logo-oshw
    check all the version numbers, board, schematic, readme and zip filename (to be created)

board submission
    print layout
    check connector placement
    create readme.txt with fudicial placement
    cam 4 layer
        gerb274x-4layer.cam
            make sure layer 51 tDocu is in plc, side silkscreen CMP
            make sure layer 200 bmp  is in plc, side silkscreen CMP
        excellon.cam
    gerbv *.crc *.plc *.stc *.cmp *.ly2 *.l15 *.sol *.sts *.pls
    run Centroid_ScreamingCircuits_smd.ulp
    update version and rev in readme.txt, add version/rev to sheet 1 of sch
    zip gerber.zip *.cmp *.crc *.crs *.drd *.dri *.gpi *.l15 *.ly2 *.plc *.pls *.sol *.stc *.sts readme.txt *centroid.csv *.dim
    zip -sf gerber.zip
        verify that sch and brd are NOT included in gerber zip file
    mv gerber.zip to board-v0.0-gerber.zip
    print sch and brd as pdf
    zip board-v0.0-release.zip board-v0.0-gerber.zip *.sch *.brd *.pdf *.pdf *.csv
        mv 2 zip files to ../release dir
    freedfm

board submission itead
    download cam file
    cam iteadstudio*.cam
    gerbv   *.GTO *.GTS *.GTL *.GBL *.GBS *GBO
    zip a.zip *.GTL *.GBL *.GTS *.GBS *.GTO *.GBO *.GBP *.GML *.GTP *.do *.TXT *.dri *.gpi readme.txt
    mv a.zip to boardname-v?.?.zip

    rm -i *.GTL *.GBL *.GTS *.GBS *.GTO *.GBO *.GBP *.GML *.GTP *.do *.TXT *.dri *.gpi

pre-assembly
    send connector drawing showing pin 1 indicator
    verify IC pin1 indicators



------------------------------------

cat > readme.txt << EOF
This information, board files, assembly instructions and bill of
materials are company confidental.
Not for distribution.

board
    ???

version
    ???

date
    ???

svn revision
    ???

fudicials at
    x,y
    x,y

2 layer description
    2 layer board
        crc component cream
        plc component side silkscreen
        stc component side solder stop mask
        cmp component side copper
        sol solder side copper
        sts solder side solder stop mask
        pls solder side silkscreen
        crs solder cream

        drd drill data
        dri drill info
        gpi gerber info

2 layer stack up sequence
    top     x.cmp
    bottom  x.sol

4 layer description
    4 layer board
        crc component cream
        plc component side silkscreen
        stc component side solder stop mask
        cmp component side copper
        ly2 layer2
        l15 layer15
        sol solder side copper
        sts solder side solder stop mask
        pls solder side silkscreen
        crs solder cream

        drd drill data
        dri drill info
        gpi gerber info

4 layer stack up sequence
    top     x.cmp
    inner 2 x.ly2
    inner 3 x.l15
    bottom  x.sol




2 layer description - using itead's cam
    Silk Top:                   pcbname.GTO
    Solder Stop Mask Top:       pcbname.GTS
    Top layer:                  pcbname.GTL
    Bottom layer:               pcbname.GBL
    Solder Stop Mask Bottom:    pcbname.GBS
    Silk Bottom:                pcbname.GBO
    NC Drill:                   pcbname.TXT
    Drill Board Outline:        pcbname.do
    Edge Milling:               pcbname.GML
    Pad Mask Bottom:            pcbname.GBP
    Pad Mask Top:               pcbname.GTP

2 layer stack up sequence
    top     x.GTL
    bottom  x.GBL





contact info
    first last
    phone
    email

EOF